The initial installation of version 11 turning has the default speed mode set to RPM and the feed mode set to IPM for all turning operations. This is not what most lathe programmers need and requires constantly changing the selector switches in the planner.
This was partially addressed by the attached technote 131 from CAMAX.
These default settings can be changed by editing the JOS default files for
turning. If you have a standard "out of the box" installation, these are the
2 files you need to edit.
c:\sm9\Turn\Josdef\t_inch.def
c:\sm9\Turn\Josdef\t_metric.def
There is one file for inch settings and another file for metric settings. I
strongly suggest you make a backup of each before making any edits. You can
then open the files in Edit Plus, Notepad or any other text editor. In these
files you need to locate the sections labeled "step". In these sections you
need to find the entries "fdmode" and "spmode". Change their default values
from to a 1 or a 2 as described below, then save the file.
fdmode = "1" UPR
fdmode = "2" UPM
spmode = "1" SUPM
spmode = "2" RPM
In Advanced Turning there are 3 different sections for setting the default
speed modes and feed modes.
// drilling & milling (live tools)
step = -5020101
[
descrip = ""
doff = "JOS(tl_num)"
fdmode = "1"
loff = "JOS(tl_num)"
notes = ""
op = ""
section = "5020101"
spmode = "2"
tool_assignment = ""
user_name = ""
]
// turning
step = -5020201
[
descrip = ""
doff = "JOS(tl_num)"
fdmode = "1"
loff = "JOS(tl_num)"
notes = ""
op = ""
refdia = "1.0"
section = "5020201"
spmode = "1"
tool_assignment = ""
user_name = ""
]
// grooving
step = -5020202
[
boff = "0"
descrip = ""
doff = "JOS(tl_num)"
fdmode = "1"
loff = "JOS(tl_num)"
notes = ""
op = ""
refdia = "1.0"
section = "5020202"
spmode = "1"
tool_assignment = ""
user_name = ""
]
You will need to restart the turning application before the change is
effective. This change will not alter existing job files or existing steps,
only steps created after the edit. After the edit all new steps will default
to the desired feed and speed modes.
=============================================
Fred Lauzus, CAM Programming Coordinator
High Steel Structures, Incorporated
mailto:[EMAIL PROTECTED] http://www.highsteel.com
=============================================
-----Original Message-----
From: lee [mailto:[EMAIL PROTECTED]]
Sent: Wednesday, August 22, 2001 10:18 AM
To: Smartcam Mailing List (E-mail)
Subject: [mfg-smartcam] RPM and Inch/Min default change?
In the edit process step area of the job operation planner I would like to
change the Speed Mode and Feed Mode defaults to RPM and Inch/Min. Is this
difficult to do?
Advanced Turning 11.5
Lee Greer
CNC\CAD programmer
Midwest Precision Tool & Die
tech131.htm
Description: Binary data
