You could call it a template (tmp) problem. The only time the feed in the jof file is automatically accessed is in the @START, @TOOLCHG and @STEPCHG sections and the feed rate is assigned to the template variable #FEED. When you change the feed rate with a user command, such as the User Event - Feed Change, you change the value of #FEED. This value normally remains modal until the next @TOOLCHG or @STEPCHG section is encountered.
I think you can accomplish what you described by accessing the jof file from within the @ENDPROF section using the jos data tag outfeed1 @ENDPROF << #MOV> Z#ZPOS> #EVAL(#FEED=jos(outfeed1)) UPDATE(#FEED) < #DCOMP> This will reset the value of #FEED to the feed rate in the jof file. ============================================= Fred Lauzus, CAM Programming Coordinator High Steel Structures, Incorporated mailto:[EMAIL PROTECTED] <mailto:[EMAIL PROTECTED]> http://www.highsteel.com <http://www.highsteel.com/> ============================================= -----Original Message----- From: Jon Baker [mailto:[EMAIL PROTECTED]] Sent: Friday, January 25, 2002 12:57 PM To: SmartCAM List Server Subject: [mfg-smartcam] Milling question. I use Freeform, but this applies to all of the milling modules. When I use Create-Machine Event-Feed Change to modify a feed rate it works just fine, however from that point in the model forward, it keeps that feed rate. On a part I was just surfacing, I want the first cut to go slower since it is taking a full bite, but then each step over is only .005 so I want that to go faster. What I did, was slow my feed in the jos to 40ipm and after the first element, bump it to F70.0 ipm in the feed change. Then when I pull out of that surface, and start another one with the same tool-step, I would think it would update upon the down feed and profile start, however it doesn't. It keeps the 70ipm rating and runs with it. So, is this a .tmp problem? or a .smf problem, or just one of those things. I am sending my .tmp file along so you can see what I am doing in there too. Thanks for any help. Jon Baker ====================================================================== To find out more about this mailing list including how to unsubscribe, send the message "info mfg-smartcam" to [EMAIL PROTECTED] ======================================================================
