Tricky, but I have done it before. In the planner you need to define 2 separate steps with identical tooling. You must identify the correct cut direction and offset register(Doff) for each tool.
As an option, to have the Show Path run correctly you must also identify the difference between the tool tips in the planner using the Xset and Zset values. (and set smf question #66 to 3. Now the tricky part is to assign the same tool number to BOTH of these tools. The planner will not allow you to do this, but it can be done in a text editor or by using a macro. In reality SmartCAM only requires a unique tool ID string. In most applications this string is hidden from the user. In turning however it is displayed as a combination turret:tool number, (i.e. 1:1). The tool number itself is used by the code generator can be anything. If the tool numbers are the same the code generator considers it a step change only and not a tool change. In the template file, you need to have a @STEPCHG section containing the #TOFF variable output @STEPCHG T#TOFF Attached are all my sample files and the macro I use to change the station number. GrooveX.pm4 Sample process model file turning both sides of a groove with 2 tools with different offsets but sharing a single tool number. GrooveX.jof Sample job file showing duplicate tool numbers for different tools to be used with GrooveX.pm4. GrooveX.smf Sample machine define file. GrooveX.tmp Sample machine template file for outputting offset changes. GrooveX Sample G code file created using the above files. CHG_STA.mcl Macro used to create duplicate tool numbers in planner. This macro is best set up as an icon button and called with the planner open to the tool list. ============================================= Fred Lauzus, CAM Programming Coordinator High Steel Structures, Incorporated mailto:[EMAIL PROTECTED] http://www.highsteel.com ============================================= -----Original Message----- From: Donald Stockham [mailto:[EMAIL PROTECTED]] Sent: Wednesday, March 27, 2002 1:55 PM To: [EMAIL PROTECTED] Subject: [mfg-smartcam] two offsets for same tool Could some one help me with the necessary template work to get a coded file that uses, for example a face grooving tool with tip 3 "DL" (T0505) and tip 2 "UL" (T0515). I would like to use tools 5 and 15 in the planner, and when my control cancels it uses T0500. I am trying to figure out how to have the planner treat them as two seperate tools but the coded file treats them as the same tool with a different tip offset. This is difficult because the planner updates the tool throughout the file, when you use "choose tool". I am sure this is confusing so here is a small sample of what I want to get: N40 T0515 ( / STEP10 ) N50 G97 S1000 M03 ( TIP2 UL R0.01 ) N60 M08 N250 G40 G00 X5. Z1.0 N260 G41 X4.55 Z0.11 N270 G01 Z0.0 N280 X4.3925 N290 G02 X4.3825 Z-0.0091 R0.01 N300 G01 X4.379 Z-0.05 N310 X4.3325 N320 G40 G00 X4.3495 Z0.1 N360 T0505 ( / STEP20 ) N370 G99 G97 S1000 M03 ( TIP3 DL R0.01 ) N380 M08 N390 G42 G01 X4.7995 Z0.0035 F0.003 N400 X4.8404 Z0.0 N410 G03 X4.8495 Z-0.0091 R0.01 N420 G01 X4.853 Z-0.05 N430 X4.8995 N440 G40 G00 Z1.0 N450 G00 X4.0 Z6.0 M9 N460 T0500 ( TIME = 0 MIN 25 SEC ) thank you, Don Stockham ====================================================================== To find out more about this mailing list including how to unsubscribe, send the message "info mfg-smartcam" to [EMAIL PROTECTED] ======================================================================
GROOVEX
Description: Binary data
GROOVEX.jof
Description: Binary data
GROOVEX.pm4
Description: Binary data
GrooveX.smf
Description: Binary data
GrooveX.tmp
Description: Binary data
CHG_STA.MCL
Description: Binary data
