Thanks Fred I did not have my geometry in one continuos profile.
John W.
-----Original Message-----
From: Lauzus, Frederick <[EMAIL PROTECTED]>
To: John Wright <[EMAIL PROTECTED]>; [MFG-SMARTCAM]
<[EMAIL PROTECTED]>
Date: Tuesday, August 22, 2000 11:27 AM
Subject: RE: [mfg-smartcam] THREAD PROFILE
>John,
>
>You will need to draw your threading tool in a .sh3 file and associate that
>file
>with the tool you are using. This will work for Show Path and Show Cut, but
>the
>thread form displayed in the graphic view (wireframe) will always be a
sharp
>V.
>
>If you did a typical install, there should be sample .sh3 files installed
in
>your Turn\Tctg folder.
>The SmartCAM Production Turning Users Guide starting on page 111 has more
>details. An
>item they neglect to mention is that the tool "must" be drawn on the
>XY_PLANE. People tend
>to forget that the default plane in turning is the ZX_PLANE. You will need
>to change both your
>active plane and your view orientation for the XY_PLANE. The active plane
is
>set in the insert
>bar. The view can be set with the Dynamic View function by selecting the
>XY_PLANE as the
>Workplane.
>
>
>The following is an excerpt from the SmartCAM Production Turning Users
Guide
>page 113.
>
>Creating a CTG for Show Cut
>You can make your own custom tool graphics for Show Cut by creating a file
>that contains a profile
>of the tool's perimeter.
>
>1. Use File-New to start a new model.
>
>2. To create the cutting portion of the tool, make the following settings
in
>the Insert property bar:
>
> * Set the Layer/Step selector switch to On Layer and enter 1 in the
>Layer/Step indicator field.
>
> * Set the Sequence Type selector switch to Profile, and enter 1 in the
>Insert Location
> indicator field.
>
> SmartCAM requires that the Show Cut CTG profile is the first profile
>on layer 1.
>
> * Enter zero in the Profile Top indicator field.
>
> * Create a closed profile of the tool perimeter using basic elements
>such as lines and arcs.
>
> For a turning tool, create the geometry as shown in figure 6-13. For
>most turning tools,
> place the nose radius center point at X0, Y0.
>
> For turning hole tools, define the tool and holder geometry as shown
>in figure 6-14. Place
> the tool tip on the origin point (X0, Y0, Z0).
>
> If you want to include the insert holder as part of the cutting tool,
>it must be included as part
> of the tool perimeter's closed profile.
>
> All elements of the Show Cut profile must be in a continuous sequence
>with no gaps.
>
>3. Use File-Save As to save the Show Cut CTG as a 3-D (.sh3) file in the
>custom tool graphics
> directory.
>
> Make sure that you save your file to the same directory as all other CTG
>files. The pturn.ini
> file includes a reference for the directory containing the CTG files. If
>you change the directory
> name or location, you must update the pturn.ini file to match the
>changes.
>
>
>
>=============================================
> Fred Lauzus, CAM Programming Coordinator
> High Steel Structures, Incorporated
> mailto:[EMAIL PROTECTED] http://www.highsteel.com
>=============================================
>
>
>
>
>-----Original Message-----
>From: John Wright [mailto:[EMAIL PROTECTED]]
>Sent: Tuesday, August 22, 2000 10:10 AM
>To: [MFG-SMARTCAM]
>Subject: [mfg-smartcam] THREAD PROFILE
>
>
>Hi,
>Is there any way to change the tool graphic for threading?(example like a
>acme)
>in p turn 11.1 so the show cut will work right.
>
> Thanks John Wright
>
>======================================================================
>To find out more about this mailing list including how to unsubscribe,
>send the message "info mfg-smartcam" to [EMAIL PROTECTED]
>======================================================================
>
======================================================================
To find out more about this mailing list including how to unsubscribe,
send the message "info mfg-smartcam" to [EMAIL PROTECTED]
======================================================================
