Re: [PEDA] Highlighting dead copper on P99SE
At 03:44 PM 8/9/2002 -0700, Brad Velander wrote: Abd ul-Rahman, Could you please elaborate on why you find it difficult to copy a polygon to another layer? temporary amnesia. :-) Thanks to Brad from me for reminding me. * Tracking #: 5B38503CEC9DC14C9B9ACFED2BF68BD3EB17FB4D * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
No problem guy, you know that we all have different ways of doing things so I was looking to learn which method didn't work and out of it maybe something else. Sincerely, Brad Velander -Original Message- From: Abd ul-Rahman Lomax To: Protel EDA Forum Sent: 11/08/2002 9:59 AM Subject: Re: [PEDA] Highlighting dead copper on P99SE At 03:44 PM 8/9/2002 -0700, Brad Velander wrote: Abd ul-Rahman, Could you please elaborate on why you find it difficult to copy a polygon to another layer? temporary amnesia. :-) Thanks to Brad from me for reminding me. * Tracking #: 360318F7ACE0C3428727214A16CE4218ECFAD1BF * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
[PEDA] Highlighting dead copper on P99SE
Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) Regards, Kat. ** K.A.Q. Electronics. Electronic and Software Engineering. Perth, Western Australia. Ph +61 (0) 419 923 731 ** * Tracking #: ACB1799E047E80499CA7990312B01378BD77700C * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
select connected copper Dennis Saputelli Katinka Mills wrote: Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) Regards, Kat. ** K.A.Q. Electronics. Electronic and Software Engineering. Perth, Western Australia. Ph +61 (0) 419 923 731 ** * Tracking #: ACB1799E047E80499CA7990312B01378BD77700C * -- ___ www.integratedcontrolsinc.comIntegrated Controls, Inc. tel: 415-647-04802851 21st Street fax: 415-647-3003San Francisco, CA 94110 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Do an Edit-Select-ConnectedCopper and you'll get a highlighted poly plane for everything that IS connected. It will be obvious what IS NOT connected and you can populate that with stitching vias or pads. Tony -Original Message- From: Katinka Mills [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 9:42 AM To: Protel EDA Forum Subject: [PEDA] Highlighting dead copper on P99SE Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) Regards, Kat. ** K.A.Q. Electronics. Electronic and Software Engineering. Perth, Western Australia. Ph +61 (0) 419 923 731 ** * Tracking #: ACB1799E047E80499CA7990312B01378BD77700C * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
At 12:41 AM 8/10/2002 +0800, Katinka Mills wrote: Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) isolated copper? I'm surprised that it generates isolated copper. I can't think of a good reason to do that.. * Tracking #: 6CBA8AFABF308645B4F4718F27AFD3FD2CCE213F * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Tony, that will only select copper connected to the single net that you click on. You would have to individually click every net on the board to highlight all copper other than the dead copper. I did a quick test trying to globally select all copper that was no net, it failed miserably. It was actually selecting copper that was assigned to other nets. Don't know why but I didn't reply to Kat because my test had failed trying to globally select no net copper. I had two pieces of copper that were intentionally set to no net, my global selection selected 5 pieces of copper, three were on another net. I think it is one of those Protel features. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: Tony Karavidas [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 10:07 AM To: 'Protel EDA Forum' Subject: Re: [PEDA] Highlighting dead copper on P99SE Do an Edit-Select-ConnectedCopper and you'll get a highlighted poly plane for everything that IS connected. It will be obvious what IS NOT connected and you can populate that with stitching vias or pads. Tony * Tracking #: 9E286F365DB17543BFF96E0C042EFFA80ACA1686 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Deselect Remove Dead Copper on Polygon Pour Setup Dialog box. Repour Polygon(s). Brian At 12:10 PM 8/9/02 -0500, you wrote: At 12:41 AM 8/10/2002 +0800, Katinka Mills wrote: Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) isolated copper? I'm surprised that it generates isolated copper. I can't think of a good reason to do that.. * Tracking #: 6CBA8AFABF308645B4F4718F27AFD3FD2CCE213F * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
A solution that just came to mind after re-reading the original post. Generate your polygon with remove dead copper checked. After pouring select the polygon and copy it to another layer without repouring. Regenerate the original copper pour with remove dead copper unchecked. Turn on the two layers with the polygons, use the original copied polygon as a mask to show you the dead copper polygons. Repeat for other board layer and then delete copied polygons when completed. You could use transparent layer viewing to advantage with this method. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: David VanHorn [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 10:10 AM To: Protel EDA Forum; Protel EDA Forum Subject: Re: [PEDA] Highlighting dead copper on P99SE At 12:41 AM 8/10/2002 +0800, Katinka Mills wrote: Hi all, Quick Q, I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) Should be easy, but the help menu has no topic on dead copper (does not even find the word dead ?? ) isolated copper? I'm surprised that it generates isolated copper. I can't think of a good reason to do that.. * Tracking #: 297607521AC609468A67BE4F93A1BC5DEA558BAE * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Yeah, I guess I was assuming the net connected to her power polygon has a 'majority' of it connected. If she does what I indicated, it will be obvious what parts of her polygon pour (which is a outer layer ground plane) are not actually connected. It will also be obvious if two or more large sections are not connected to each other (but a DRC should point that out quickly too) Tony -Original Message- From: Brad Velander [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 10:29 AM To: 'Protel EDA Forum' Subject: Re: [PEDA] Highlighting dead copper on P99SE Tony, that will only select copper connected to the single net that you click on. You would have to individually click every net on the board to highlight all copper other than the dead copper. I did a quick test trying to globally select all copper that was no net, it failed miserably. It was actually selecting copper that was assigned to other nets. Don't know why but I didn't reply to Kat because my test had failed trying to globally select no net copper. I had two pieces of copper that were intentionally set to no net, my global selection selected 5 pieces of copper, three were on another net. I think it is one of those Protel features. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: Tony Karavidas [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 10:07 AM To: 'Protel EDA Forum' Subject: Re: [PEDA] Highlighting dead copper on P99SE Do an Edit-Select-ConnectedCopper and you'll get a highlighted poly plane for everything that IS connected. It will be obvious what IS NOT connected and you can populate that with stitching vias or pads. Tony * Tracking #: 9E286F365DB17543BFF96E0C042EFFA80ACA1686 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
First off thanks to all who responded :o) -Original Message- From: Brad Velander [mailto:[EMAIL PROTECTED]] Sent: Saturday, 10 August 2002 1:29 AM To: 'Protel EDA Forum' Subject: Re: [PEDA] Highlighting dead copper on P99SE Tony, that will only select copper connected to the single net that you click on. You would have to individually click every net on the board to highlight all copper other than the dead copper. I did a quick test trying to globally select all copper that was no net, it failed miserably. It was actually selecting copper that was assigned to other nets. Don't know why but I didn't reply to Kat because my test had failed trying to globally select no net copper. I had two pieces of copper that were intentionally set to no net, my global selection selected 5 pieces of copper, three were on another net. I think it is one of those Protel features. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com Hmmm another feature ;o) OK all here is how i did it, and it worked for me YMMV I selected all copper connected on the top layer, switched to botom and did the same, then placed vias on each dead section, rebuilt top and botom planes seperately, and kept repeating till I was happy I had the best coverage posible :o) Thanks all once again :o) I am off to bed it is 2:04am lol Regards, Kat. ** K.A.Q. Electronics. Electronic and Software Engineering. Perth, Western Australia. Ph +61 (0) 419 923 731 ** * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * Tracking #: AC2BF5E77F40A046A27FEA606C523A6FF719D4F8 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Tony, if you read my message following this one that you replied to, you will realize that I had misread the original message. Your method would probably work as an inversion to the original request, highlighting the connected polygon. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: Tony Karavidas [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 11:02 AM To: 'Protel EDA Forum' Subject: Re: [PEDA] Highlighting dead copper on P99SE Yeah, I guess I was assuming the net connected to her power polygon has a 'majority' of it connected. If she does what I indicated, it will be obvious what parts of her polygon pour (which is a outer layer ground plane) are not actually connected. It will also be obvious if two or more large sections are not connected to each other (but a DRC should point that out quickly too) Tony * Tracking #: B43F029E68221540AECE9E243F69BAF7DD9B5BEA * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
Yeah Abd ul-Rahman, I had thought of that as a possibility, just hadn't had time to test that possibility. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: Abd ul-Rahman Lomax [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 1:54 PM To: Protel EDA Forum Subject: Re: [PEDA] Highlighting dead copper on P99SE It's a known bug, at leat I think it has been reported before. I don't recall all the details. It may be related to the bug that Mr. Velander has reported in the bug database (in the filespace for [EMAIL PROTECTED]), regarding polygon pours and no-net entities. * Tracking #: 75C899E7F6DD5E46BA250F7E3679034D23279BD5 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
Re: [PEDA] Highlighting dead copper on P99SE
At 12:41 AM 8/10/2002 +0800, Katinka Mills wrote: I have a 2 layer PCB with top and bottom ground planes (like to balance up my copper) how do I hilight dead copper, I do not want to remove it, just need to see it so I can add vias to make it not dead :o) As has been noted, there is a remove dead copper option in the polygon pour dialog. However, Ms. Mills does not want to remove said copper, but to connect it. I do this regularly. It has been suggested to use select connected copper to highlite what is connected, thus leaving the unconnected polygon copper standing out like a sore thumb. Unfortunately, select connected copper does not function where connections are made through vias to a power plane. However, connections made through a physical layer are selected by this command, so if this is a simple 2-layer board, it will work. A workaround would be to create an extra temporary inner layer and pour the entirely layer with the net in question. But that is probably more trouble than it is worth. The job might be done, I think, a number of different ways. I might simply examine the area of the polygon, wiht dead copper removed, for spots large enough to drop a via. This is easy to do with a via floating on the cursor and on-line DRC active. This is how I do it. Note that the via, while it is floating, will show violations (if on-line DRC), but those will disappear if it is popped down onto a netted object (vias and pads generally take on the net of objects which they contact while being placed, if the placement does not create a short.) If, while the via is floating, one hits TAB and assigns the pour net to the via, it will only show real violations, i.e., to other nets, perhaps on another layer. (violating track on other layers will display under these conditions, making it fairly easy to find spaces that do not violate.) Polygon primitives, while still associated with the polygon, are *not* assigned any net, which you can find by unlocking the polygon primitives so that they can be individually edited; rather the polygon as a whole carries the net. So in this respect, dead copper track and connected track are the same. Exploding the polygon with Tools/Convert assigns the net to all the polygon tracks, including any dead copper. Normally, global edits can be done on no-net track to highlight it, but, as mentioned, all polygon track is no-net; Protel thus locks it out from global edits, just as it locks out polygon track from other global edits (for example, a global edit with width scope matching the polygon pour width). However, I just discovered that if I unlock the primitives of a polygon, and double-click on one track, and then do a global edit on the track with net scope, all polygon track is highlighted, as well as all non-polygon no-net track. (Remember, all polygon track is no net, even if the polygon has a net.) One might think that this could be used to copy all polygon track to another layer, but, n: selected polygon track is not placed on the clipboard by Edit/Copy/Click. However, it is not difficult to copy a polygon to a mech layer (be sure to have dead copper removal turned off, or you will have a famous Protel Invisible Polygon, a general nuisance). Then one repours the original polygon with dead copper removed. In this way dead copper regions can be contrasted with connected ones. But normally this is not necessary, it is quite simple to look for empty regions within the area of a pour, as I mentioned above. Select Net does *not* select polygons belonging to the net. Some of this behavior could really be classified as a bug, rather than as merely a missing feature. There should be a check box in the polygon dialog allowing selected of the polygon. Instead more convoluted ways may be necessary in order to select a polygon for copy. Polygons will pick up (Leftclick-Drag), a fact that is more of a nuisance than a feature. However, the Query Manager allows the selection of polygons by various criteria; but such a polygon cannot be copied to another layer without repouring it. If it is repoured, it takes on the shapes appropropriate to that layer. Furses, coiled again! I do not find it easy to copy a polygon to another layer, keeping it poured exactly as it was originally poured, without also copying other stuff. It would probably be necessary to explode the polygon, I have not explored what happens, for example when selected polygon primitives are exploded. * Tracking #: 3B1443FE6E30C7438EC8B8CA9EA73C497156BE51 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines
Re: [PEDA] Highlighting dead copper on P99SE
Abd ul-Rahman, Could you please elaborate on why you find it difficult to copy a polygon to another layer? I can do it without any effort whatsoever. I knew I had done it in the past. However what I had forgotten and just rediscovered is that the polygon does not change layer colour until you repour it which is one of things that you would not want to do in this instance. So you would have the unchanged polygon on another layer but it would look as though it is on the old layer colour-wise. To copy the polygon I used the Shift-Click selection process, Ctrl-Insert to copy, change layer to a mech layer, use Edit Paste special with paste on current layer checked, click where you want it. When it asks to repour the polygon, click no. The rest of the process is: Once it is pasted on the layer that you want it on, first deselect all to clear all prior selections. Then edit the copied polygon properties to unlock the primitives, DON'T REPOUR. Use Select Connected Copper on the copied polygon primitives. Edit one polygon track and globally change the layer of all selected polygon tracks using selection Same, deselect all. You now have a copy of your precise polygon on a mech layer in the correct colour for the mechanical layer you copied it to. During the global edit of the copied polygon primitives you can also change their net or other characteristics if that did anything for you. Once you know the steps, you could copy the poured polygon to a mech or other layer without changing it's shape in approx. 10 seconds flat. Sincerely, Brad Velander. Lead PCB Designer Norsat International Inc. Microwave Products Tel (604) 292-9089 (direct line) Fax (604) 292-9010 email: [EMAIL PROTECTED] http://www.norsat.com -Original Message- From: Abd ul-Rahman Lomax [mailto:[EMAIL PROTECTED]] Sent: Friday, August 09, 2002 2:53 PM To: Protel EDA Forum; Protel EDA Forum Subject: Re: [PEDA] Highlighting dead copper on P99SE SNIP I do not find it easy to copy a polygon to another layer, keeping it poured exactly as it was originally poured, without also copying other stuff. It would probably be necessary to explode the polygon, I have not explored what happens, for example when selected polygon primitives are exploded. SNIP * Tracking #: BD249A4008784549B7F2A063766965320421F192 * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * To post a message: mailto:[EMAIL PROTECTED] * * To leave this list visit: * http://www.techservinc.com/protelusers/leave.html * * Contact the list manager: * mailto:[EMAIL PROTECTED] * * Forum Guidelines Rules: * http://www.techservinc.com/protelusers/forumrules.html * * Browse or Search previous postings: * http://www.mail-archive.com/proteledaforum@techservinc.com * * * * * * * * * * * * * * * * * * * * * * * * * * * * * *
